DFMA: SHOULD COSTING
DFMA: PRODUCT SIMPLIFICATION
The three cost pillars of injection molding
Injection molding part cost breaks into three independent components: material cost, processing cost, and tooling cost. Each pillar responds differently to design changes, process parameters, and production volume. Understanding this structure is essential for accurate estimation and for identifying which design changes deliver cost reduction.
The formula that ties them together is deceptively simple, but the variables within each component are rich with opportunity for optimization. This guide walks through the cost structure, explains the physics and economics behind each driver, and shows how to estimate injection molding costs yourself.
On this page
The three cost pillars
Injection molding part cost is the sum of three independent cost components. Each responds to different design and process variables. Separating them helps you understand which levers actually move the cost dial.
Resin cost per unit weight multiplied by shot weight. Includes part weight, runner weight, and scrap. Color additives and material grades affect unit cost.
- Commodity: $1–$2/kg
- Engineering: $3–$5/kg
- High-performance: $10–$20+/kg
- Varies by resin grade & supplier
Machine rate (depreciation, overhead, floor space) multiplied by cycle time, divided by parts per cycle. Wall thickness and clamping force are primary drivers.
- Machine rate: $40–$120/hour
- Cycle time: 10–120+ seconds
- Scales with clamp force
- Cooling time ≈ wall thickness2
Mold base, cavity/core manufacture, design and engineering, hot runner system, side pulls, lifters. Cost amortized over production volume.
- Simple: $3k–$10k
- Medium: $10k–$50k
- Complex: $50k–$300k+
- Cost per part ≍ ÷ volume
Material cost deep-dive
Material cost = resin cost per kilogram × shot weight. Shot weight includes the part weight, runner weight (plastic that connects the part to the sprue in the mold), and scrap lost during mold open. Resin cost varies dramatically by material grade and supplier.
Resin Cost by Material Category
| Material Category | Examples | Cost Range | Notes |
|---|---|---|---|
| Commodity plastics | PE, PP, PS | $1–$2/kg | Lowest cost, highest volume. Price volatile with oil markets. |
| Engineering resins | ABS, PC, Nylon, POM | $3–$5/kg | Higher stiffness, temperature resistance. Moderate volume. |
| High-performance | PEEK, PEI, LCP | $10–$20+/kg | Extreme temperature, chemical resistance. Low volume applications. |
Shot Weight and Scrap
Shot weight = part weight + runner weight + startup/shutdown scrap. Runners are necessary plastic connecting the mold cavity to the sprue (the inlet point). Runner weight is waste—but can sometimes be ground and regrind-blended back into new resin (5–15% yield loss typical).
Color additives increase resin cost by 5–15%, depending on pigment type and intensity. Flame-retardant or UV-stabilized grades add 10–30% to base resin cost. Reinforced plastics (glass-filled nylon, carbon-reinforced) cost 20–50% more than unreinforced base resin.
Material Cost Formula
Material Cost per Part = (Resin Cost/kg) × (Shot Weight in kg) ÷ (1 – Scrap Rate)
Example: ABS at $4/kg, 25g part + 12g runner (37g shot), 8% scrap rate = ($4 ÷ 1000 kg/kg) × (37g ÷ 1000) ÷ (1 – 0.08) = $0.16/part material cost.
- Reduce part weight: thin walls, remove material pads, optimize draft angles
- Use cheaper resin: commodity plastic instead of engineering grade where specs permit
- Multi-cavity molds: spread sprue/runner cost across more parts
- Hot runner systems: eliminate most runner waste (cost tradeoff)
- Negotiate volume pricing: 5% resin cost reduction at 1M+ volume
- Part geometry (except total weight)
- Mold quality or cavity finish
- Cycle time or machine size
- Production volume (per-part is linear)
- Clamping force or injection pressure
Processing cost deep-dive
Processing Cost = (Machine Rate in $/hour) × (Cycle Time in hours) ÷ (Parts per Cycle). Processing cost is the operating cost of the injection molding machine. Larger machines (higher clamping force) cost more to operate. Longer cycle times cost more per part. More cavities (more parts per cycle) spread the cost across more parts.
Machine Rate by Clamping Force
| Clamp Force (tons) | Machine Class | Rate Range | Application |
|---|---|---|---|
| 50–150 | Small | $40–$60/hr | Thin-wall commodity parts, small connectors |
| 150–500 | Medium | $50–$80/hr | General purpose, medium parts, automotive clips |
| 500–1000 | Large | $70–$110/hr | Large parts, thick walls, complex geometry |
| 1000+ | Extra-large | $90–$150/hr | Large complex parts, multi-cavity molds |
Cycle Time and Wall Thickness
Cycle time = fill time + cooling time + mold reset (typically 3–4 seconds). Fill time is usually 2–5 seconds for typical parts. Cooling time dominates and follows a critical relationship: cooling time is proportional to wall thickness squared.
This quadratic relationship is why design for injection molding emphasizes uniform wall thickness (2.5–3.5mm nominal) and avoids thick sections. A 1mm reduction in average wall thickness can cut cycle time 20–40%, a massive cost improvement.
Clamp Force and Injection Pressure
Clamp force (tons) = Injection pressure (MPa) × Projected area (cm²) ÷ 10. Projected area is the shadow of the part when viewed from the parting line. Larger parts and thicker walls (higher pressure needed to fill) require larger clamp forces and more expensive machines. This relationship makes envelope size and wall thickness primary drivers of machine cost.
- Reduce wall thickness: 1mm reduction = ~25% cycle time cut
- Optimize cooling design: conformal cooling, water channels
- Uniform wall thickness: eliminates thick sections, improves fill
- Multi-cavity molds: 4-cavity = 75% processing cost per part
- Automatic vs. manual: automation adds machine rate but cuts cycle time
- Runner design: hot runners eliminate fill time waste
- Every 1 second of cycle time saved = $22k/yr at 1M parts, $80/hr rate
- One-cavity, 45s cycle, 4-cavity, 50s cycle same machine rate
- Automatic operation (robot) adds $20–$30/hr but eliminates manual labor downtime
- Setup cost (part/tool change) amortized separately, not in cycle time
Processing Cost Formula
Cost per Part = (Machine Rate $/hr) × (Cycle Time seconds) ÷ (Parts per Cycle) ÷ 3600 seconds/hr
Example: 200-ton machine at $65/hr, 50s cycle, 4 cavities = ($65 × 50 ÷ 4 ÷ 3600) = $0.23/part processing cost.
Tooling cost deep-dive
Tooling Cost = Mold base + cavity/core manufacture + design & engineering + hot runner system + side pulls/lifters. Tooling cost is amortized across the production volume, so its per-part impact decreases as volume increases. However, tooling decisions made during design lock in much larger processing costs.
Mold Cost by Complexity
| Mold Category | Cavities | Cost Range | Characteristics |
|---|---|---|---|
| Simple (student molds) | 1 | $3,000–$10,000 | Flat parts, minimal draft, no cores, aluminum mold base |
| Medium complexity | 1–4 | $10,000–$50,000 | Standard part geometry, minimal inserts, basic cooling channels |
| Complex | 4–8 | $50,000–$150,000 | Multiple side pulls, lifters, hot runners, precision inserts |
| High-volume production | 8–24 | $150,000–$300,000+ | Multiple cavities, complex features, precision steel molds, hot runner |
Cost Drivers Within Tooling
- SPE#1 (mirror): polished, reflective
- SPE#2: smooth, slight gloss
- SPE#4: fine matte surface
- SPE#6 (minimum): rough, tooling marks visible
- Cost impact: SPE#1 adds 30–50% to cavity cost vs. SPE#6
- Side pulls: increase cavity count limit to 1–4 per config
- Lifters (cams): undercut features, complex motion
- Unscrewing cores: for threaded inserts, ~$2k–$5k each
- Hot runner system: $5k–$20k depending on cavity count
- Precision inserts: brass, steel, threaded, heat-set
Cavity Count Optimization
More cavities = higher mold cost, lower cost per part. However, cavity count is constrained by mold dimensions (machine platens typically 300×300 to 500×500mm), cooling capability, and the need to balance cavity fill times (unbalanced fill causes quality problems).
Cavity life: varies by material. Commodity plastics (PE, PP) may run 2–3 million cycles before cavity wear becomes visible. Engineering plastics (ABS, Nylon) typically 1–2 million. Filled resins and reinforced plastics wear cavities faster (abrasive filler particles). Tooling material choice (aluminum vs. P20 vs. H13 steel) affects both cost and cavity life significantly.
Tooling Cost Formula
Tooling Cost per Part = Total Mold Cost ÷ Production Volume
Example: $40k mold for 500k volume = $0.08/part tooling cost. Same mold at 1M volume = $0.04/part. At 100k volume = $0.40/part (significant!).
- Increase volume: tooling cost per part ≍ ÷ volume
- Multi-cavity molds: 4-cavity mold costs ~2.5× but makes 4 parts/cycle
- Minimize complexity: simple parting line, no side pulls, no unscrewing cores
- Standard mold base: off-the-shelf bases are cheaper than custom
- Aluminum molds: faster/cheaper to manufacture, suitable for <500k volumes
- Design for moldability: uniform draft, rounded corners, no tight tolerances on all dimensions
How to estimate injection molding cost yourself
With the three cost pillars and the underlying formulas, you can build a quick cost estimate using only design parameters and process assumptions. You do not need detailed CAD or supplier quotes. Here is the step-by-step approach.
Step 1: Estimate Material Cost
1a. Determine resin type (PE/PP, ABS, PC, Nylon, etc.) and base cost: commodity $1–$2/kg, engineering $3–$5/kg.
1b. Estimate part weight: use CAD or approximation (length × width × thickness × average density). ABS ~1.05 g/cm³, PC ~1.2, Nylon ~1.14.
1c. Estimate runner weight: typically 40–60% of part weight for single-cavity, or lookup from similar parts. Multi-cavity molds share sprue, reducing per-part runner waste.
1d. Calculate shot weight = part weight + runner weight + 5% startup/shutdown scrap.
1e. Material Cost = (resin cost/kg) × (shot weight kg) ÷ 0.95 yield.
Step 2: Estimate Processing Cost
2a. Estimate maximum wall thickness (thickest section in part) in mm.
2b. Estimate cooling time using rule of thumb: Cooling time (s) ≈ 1 second per mm² of cross-sectional area at wall thickness. For a 3mm wall, typical cooling 20–30s. For 4mm, 35–45s.
2c. Estimate fill time: 2–5 seconds typically, depending on cavity volume and injection pressure.
2d. Cycle time = fill time + cooling time + 3 seconds mold open/close/reset.
2e. Estimate projected area (shadow of part viewed from parting line). Use CAD bounding box or estimate as length × width at parting line plane.
2f. Estimate clamp force = (20 MPa × projected area cm²) ÷ 10. Choose machine from table above based on clamp force.
2g. Assume cavities (1 for low volume, 2–4 for medium volume, 4–8+ for high volume).
2h. Processing Cost per Part = (machine rate $/hr × cycle time s ÷ cavities) ÷ 3600 s/hr.
Step 3: Estimate Tooling Cost
3a. Assess part complexity: simple (flat, minimal draft) = $3k–$10k single-cavity. Medium (standard geometry) = $15k–$40k. Complex (side pulls, lifters) = $50k–$150k.
3b. Adjust for cavities: each additional cavity adds ~30–60% to mold cost (depends on mold base size and cooling).
3c. Adjust for hot runner (if needed for multi-cavity): add $5k–$15k.
3d. Tooling Cost per Part = Estimated Total Mold Cost ÷ your expected production volume.
Step 4: Sum the Three Pillars
Total Cost per Part = Material Cost + Processing Cost + Tooling Cost
This estimate is typically ±20–30% accurate at concept stage. Accuracy improves to ±10–15% with more detailed design information (exact wall thickness, detailed geometry, confirmed cavity count, and regional machine rates).
Worked example: four-cavity mold at 500k volume
Consider a black ABS connector: 18g part, designed for a 4-cavity mold, 500,000 units/year volume. Let us walk through the estimate step by step.
Material Cost
- Resin: black ABS = $4.20/kg (base commodity ABS $3.50/kg + black pigment $0.70/kg)
- Part weight: 18g (from CAD or approximation)
- Runner weight (4 cavities, balanced runner): 8g total runner ÷ 4 cavities = 2g per part
- Startup/shutdown scrap: ~5% of shot
- Shot weight: 18g + 2g + 0.5g scrap allowance = 20.5g
- Material Cost = $4.20/kg × 0.0205kg ÷ 0.95 yield = $0.091/part
Processing Cost
- Wall thickness: 1.8mm (thin-wall design)
- Cooling time: ~20 seconds (1.8mm wall, small part)
- Fill time: 3 seconds (small cavity, low volume injection)
- Mold open/close/reset: 3 seconds
- Total cycle time: 20 + 3 + 3 = 26 seconds
- Projected area: 35cm² (small connector foot print)
- Clamp force: (20 MPa × 35 cm²) ÷ 10 = 70 tons → small 50–150 ton machine, $50/hr rate
- Cavities: 4
- Processing Cost = ($50/hr × 26s ÷ 4 cavities) ÷ 3600 s/hr = $0.090/part
Tooling Cost
- Base mold (aluminum, 4-cavity): $18,000
- Cavity manufacture & finishing (4 cavities, SPE#2 finish): $12,000
- Design & engineering: $3,000
- No side pulls, lifters, or hot runner (simple runner)
- Total mold cost: $33,000
- Production volume: 500,000 units
- Tooling Cost per Part = $33,000 ÷ 500,000 = $0.066/part
Total Cost per Part
$0.091 (material) + $0.090 (processing) + $0.066 (tooling) = $0.247 — approximately $0.25/part
At $0.25/part cost, a $0.40 selling price leaves ~37% margin for distribution, overhead, and profit. This estimate is defensible for supplier negotiation or make-vs-buy analysis. If a supplier quotes $0.35/part, you know the gap is real (margin compression, different volume assumption, or regional cost advantage).
Cost Sensitivity
| Change | Estimated Impact |
|---|---|
| Reduce wall thickness from 1.8mm to 1.5mm | -$0.015 per part (cooling time ÷ 20%, processing ÷ 15%) |
| Increase volume to 1M parts/year | -$0.033 per part (tooling cost ÷ 50%) |
| Switch to 8-cavity mold (from 4) | -$0.020 per part (tooling ÷ 50%, processing ÷ 50%, mold cost +$15k) |
| Use commodity PE instead of ABS | -$0.018 per part (material cost drops 20%) |
This example is illustrative. Actual costs depend on regional machine rates, supplier mold pricing, material market conditions, and specific design details. DFMA models these factors precisely for your geometry and process parameters.
Frequently asked questions
What determines injection molding part cost?
Injection molding cost is driven by three factors: (1) material cost (resin cost × shot weight), (2) processing cost (machine rate × cycle time ÷ parts per cycle), and (3) tooling cost (mold cost ÷ production volume). Understanding these three pillars lets you estimate cost accurately and identify which design changes have the biggest cost impact.
How much does injection molding tooling cost?
Tooling cost ranges from $3,000–$10,000 for simple single-cavity molds to $50,000–$300,000+ for complex multi-cavity molds with side pulls, lifters, or hot runner systems. Cavity/core finish (from SPE#1 mirror to SPE#6 minimum), number of cavities, and insert complexity all affect mold cost. The tooling cost per part decreases as production volume increases.
What is injection molding cycle time and how does it affect cost?
Cycle time is the time from mold closing to mold opening per cycle, including fill time, cooling time, and mold reset. Cooling time is critical and follows a quadratic relationship with wall thickness: doubling wall thickness quadruples cooling time. Machine rate ($/hour) multiplied by cycle time, divided by cavity count, determines the processing cost per part. Every second saved in cycle time saves money at scale.
How do I calculate injection molding shot weight and material cost?
Shot weight = (part weight + runner weight + scrap). Material cost per part = resin cost per kg × shot weight in kg × (1 ÷ yield rate). Commodity plastics (PE, PP, PS) cost $1–$2/kg. Engineering resins (ABS, PC, Nylon) cost $3–$5/kg. High-performance plastics (PEEK, PEI) cost $10–$20+/kg. Color additives increase resin cost. Scrap resin can sometimes be resold to offset material cost.
What is the relationship between clamp force and machine rate?
Machine costs scale almost linearly with clamping force. Clamp force = injection pressure × projected area. Projected area is the shadow of the part viewed from the parting line direction. A larger or thicker part requires higher pressure and larger clamp force, demanding a more expensive machine. This relationship makes wall thickness and envelope size major cost drivers.
How does cavity count affect mold cost and part cost?
More cavities increase mold cost but lower cost per part by spreading the mold cost over more parts per cycle. However, cavity count is limited by mold dimensions and cooling constraints. Side pull configuration determines maximum cavity count (typically 1–24 cavities). The optimal cavity count balances mold cost, machine capability, and cycle time to minimize total unit cost.
Estimate your injection molded part cost
Bring your design or a sketch. We will show the process-based cost breakdown—material, cycle time, clamping force, tooling, cavities—and demonstrate how design changes move each component. With or without CAD.
